Piloted Points and Toolpath

Cycles: Direct Grooving, Z Level, Zig Zag, W type, O Ring Type, Finish Groove

Toolpath

This command is used for the calculation of the toolpath.

The toolpath is calculated by GO2cam and takes into consideration or not the tool radius.
The pull down menu offers:

		Part(Tool center): GO2cam does not calculate offset toolpath. The ISO programming follows the geometrical contour. In the case where the tool does not pass, GO2cam recalculates a new appropriate path and manages the collision. Applicable only for Finish Groove cycle
		Tool center: GO2cam calculates the tool radius offset toolpath.
		Imaginary nose: The P point corresponds to the point "measured" in X and in Z.
		Part(Imaginary nose): The toolpath is calculated on the part and the rapid motions of cycle (take and lose of correction) and inter-cycles can be managed correctly because we know how the tool is piloted. This option enables to properly program Roughing and finishing operations with the same tool. ( Roughing toolpath in Imaginary Nose, Finishing in Part). In such a situation, it is advised to force the P Point option directly in the tool page so as to not have 2 different piloted points for the same tool. Applicable only for Finish Groove cycle

The tool is showed cutting side to the front.

This command allows you to choose the type of cutter compensation.
The pull down menu offers:

1 cutter compensation is used.

Pilot Type	Left		Center		Right		Center P
Imaginary Point / Tool Center

2 cutters compensation are used according to the sense of the profile.

The right point is piloted because the profile starts on the right.	The left point is piloted because the profile starts on the left.

2 cutter compensations are used, but you can choose the first pilot point.

Pilot Type	Left		Center		Right		Center P
Imaginary Point / Tool Center

This command is used to define the pilot points of the toolpath.

It depends on the chosen Number of pilot points.

Left: the compensation is taken into consideration on the left of the tool (columns with ‘Left’ on the above tables).
Center: the compensation is taken into consideration on the center of the tool (columns with ‘Center’ on the above tables).
Right: the compensation is taken into consideration on the right of the tool (columns with ‘Right’ on the above tables).